This validation case belongs to fluid mechanics, representing the aerodynamics of the Ahmed body study. The aim of this test case is to validate the following parameters:
- Drag coefficient computation
- Velocity profiles
The simulation results of SimScale were compared to the experimental data presented in [Ahmed]\(^1\).
Geometry
The geometry is created based on the simplified aerodynamic body used by Ahmed et al\(^1\). See Figure 1 for dimensions and Figure 2 for the geometry. The slant angle (\(\phi\)) is set to 25°. The body is placed in a wind tunnel 6 \(m\) x 5 \(m\) x 13.5 \(m\) in order to limit the aerodynamic blockage effect.
Analysis Type and Mesh
Tool Type: OpenFOAM®
Analysis Type: Turbulent Incompressible fluid flow
Mesh and Element Types:
| Mesh | Mesh Type | Number of Cells |
|---|---|---|
| Mesh 1 | Standard | 3,746,887 |
| Mesh 2 | Standard | 6,915,859 |
| Mesh 3 | Standard | 10119321 |
The Standard Mesher algorithm with tetrahedral and hexahedral cells was used to generate the mesh, with refinements near the walls and in the wake region (see Figure 3).
A typical property of the generated mesh is the \(y^+\) (“y-plus“) value, which is defined as the non-dimensionalized distance to the wall, learn more. A \(y^+\) value of 1 would correspond to the upper limit of the laminar sub-layer.
Wall treatment
- Full Resolution in the near-wall region: The first cell lies at most at the boundary of the laminar sub-layer and no further. Here, \(y^+\) value is 1 or below.
- Use of wall-functions to resolve the near-wall region: There is no need to place cells very close to the laminar sub-layer, and typically \(30 \le y^+ \le 300\).
An average \(y^+\) value of 1 was used for the inflation layer around the body, and 150 for the floor. The \(k-\omega\) SST turbulence model was chosen, with full resolution for near-wall treatment of the flow around the body and with wall function for the floor.
Simulation Setup
Material
Fluid
Air with a kinematic viscosity of 1.5 x 10-5 \(kg/ms\) is assigned as the domain fluid.
Boundary Conditions
The boundary conditions for the simulation are shown in Figure 4 below:
| Boundary Condition | Face | Value |
|---|---|---|
| Velocity inlet \([m/s]\) Turb. kinetic energy \([m^2/s^2]\) Specific dissipation rate \([1/s]\) | Inlet | 60 0.135 180.1 |
| Pressure outlet \([Pa]\) | Outlet | 0 (Fixed gauge pressure) |
| Slip wall | Side and top faces | – |
| No slip wall – Wall function | Bottom face (Ground) | – |
| No slip wall – Full resolution | Car body | – |
The free stream velocity of the simulation is 60 \(m/s\), so that the Reynolds number based on the length of the body \(L\) is 4.29e6. Those are the same values presented in the original experiment of Ahmed and Ramm\(^1\).
Reference Solution
The experimental solution is presented in Figure 4 in the reference paper\(^1\) giving the value for the drag force coefficient for the slant angle \(\phi\) = 25°:
$$ C_{d} = 0.2875 $$
Result Comparison
Drag Coefficient
The drag force is defined as
$$ F_{d}={\frac {1}{2}}\rho \,U^{2}\,C_{d}\,A_x $$
where \(A_x\) (0.115 \(m^2\)) is the projected area of the Ahmed body in the streamwise direction and \(F_{d}\) the drag force. The drag force and drag coefficient were determined by the integration of surface pressure and shear stress over the entire Ahmed body (except for the 4 stilts acting as support).
Mesh #2 was selected due to its accuracy and favorable results in relation to the simulation time. The resulting drag coefficient of the Ahmed body, closest to the reference solution as yielded by Mesh #2, was computed to be 0.2915, which is within a 1.217 % error margin of the measured value.
Table 2 shows the result of the mesh independence study:
| Mesh | DRAG FORCE \([N]\) | DRAG COEFFICIENT | REFERENCE | ERROR [%] |
|---|---|---|---|---|
| Mesh #1 | 73.776 | 0.2985 | 0.2875 | 3.65 |
| Mesh #2 | 72.043 | 0.2915 | 0.2875 | 1.217 |
| Mesh #3 | 70.186 | 0.2835 | 0.2875 | -1.39 |
The difference in the error percentage magnitude between Mesh #2 and Mesh #3 is 0.173, indicating that the drag coefficient values are acceptable.
Wake Flow Patterns
The velocity streamline contour of the mean flow obtained with the simulation is reported in Figure 5, together with experimental results of reference.
References
Note
If you still encounter problems validating you simulation, then please post the issue on our forum or contact us.